Weird behaviour of material allocation

Hi all,

I have encountered weird behaviour of material allocation where I don't understand whats happening.

I have a three point bending model set up with two different components / materials.




The pads are soft linear elastig material to reduce stress concentration.


The beam is defined es Mohr Coulomb with Mohr Coulomb Hardening. Never mind the properties, they are arbitrary at this stage.


Now the strange bit: I would expect plastic strain to occur at the bottom of the beam, but that is not the case. Infact, plastic strain is zero in the entire bearm but instead there is some plastic strain in the pads (which are linear elastic).



If I invert the material defintion, I get plastic strain in the beam but not in the pad.


The elastic properties (stiffness) is allocaded correctly, only the Mohr Coulomb part seems to be swapped.

If I allocate the pad material to both components, I get no plastic strain as expected.

If I allocate the Mohr Coulomb material to both components, I get plastic stain in the beam only. But that is due to the fact that the plasticity limit is not reached in the pads. I added a separete element with pad material to check.


I attached my sample model.

Does anyone have an idea whats happening?

Thanks a lot!

Comments

  • I think your units are wrong so never goes plastic except spots in pads. Note I also think support conditions are wrong which will result in strong arching (if non-linear geometry), and therefore a relatively restrained material increasing the mohr coulomb strength.
  • Corrected units of your Mohr Coulomb. Note in the correct units your pads are not soft.
  • And thank you. I had been looking for a working model of concrete using Mohr Coulomb. I saw references of interest, one indicating a potential with Surface codes and mecway passing the correct codes to Calculix, and another about the angle causing a lack of solution closure if too big or small. 2.0 degrees is considered enough, I would experiment with the values with small changes, not the multiple order of magnitude the wrong units causes.
  • I also think there is a bug. Regardless of the material parameters, it has not been assigned correctly. The elastic pad should not be exhibiting plastic deformation.
  • Hi,
    thanks for the reply!
    I had a look ath the model "Corrected Mohr Coulomb" that you provided.
    When I apply the material ("Mohr_Coulomb_TEST(2)") that you created in the model, indeed I do get plastic strain in the beam.
    However, if I copy and paste your material definition into the existing material inside my original model, I again have not plastic strain in the beam.
    Looking at the Input file shows that the material defintions have swapped order in your model. Probably duplicating the material and reapplying it moved it to the end in the input file.


    Stangely, it seems to me that the Mohr Coulomb Hardening is not applied to the right material defintion somehow...
    I set up a model (attached) with 4 cubes to check. Only "A" has a Mohr Coulomb material. "B", "C", and "D" are linear elastic.

    Appearently, the mohr plasticity is applied only to cube "D" for some reason.

    Input file:
    *MATERIAL,NAME=A_MOHR *ELASTIC 23500e6, 0.2 *MOHR COULOMB 37.5,36 *MOHR COULOMB HARDENING 2.5e6, 0 4.5e6,0.0005 5.2e6,0.1 *MATERIAL,NAME=B *ELASTIC,TYPE=ISOTROPIC 23500000000,0.2 *MATERIAL,NAME=C *ELASTIC,TYPE=ISOTROPIC 23500000000,0.2 *MATERIAL,NAME=D *ELASTIC,TYPE=ISOTROPIC 23500000000,0.2

    Could it be for some reason that the mohr coulomb material is alway aplied to the last material definition in the input file? I'm confused...

    With the above material definition plasticity starts at about 2MPa at a randomly selected node which is approximately what I would expect. So units should be ok, or am i missing someting?

    I don't quite understand what you meant with the wrong supports. Can you explain?

    Thanks for taking the time!
  • As far as "the supports" The load is not resisted primarily by bending if the member is fixed in translation as a diagonal force developes between the loads and the supports. fixed in trasnslation supports resist the stretching of the bottomof the beam. I was wrong as you freed one support in the X trtanslation direction so this beam will not arch. I also mentioned a known error in the Mecway/Callculix interface for problems with tie interfaces or perhaps it was node to surface coupling. Per the AI I used, apparently one or several key words transmitted from Mecway to Callculix is incorrect. I only corrected the units, i.e. I did not spend much time on this. I am at the same stage of learning Mohr-coulomb as you are. As far as the arching restraint, It might not be reflected in this type of model, only shows up in geometric non-linearity and that does not seem specifiable? Callculix handles material non-linearity, and geometric non-linearity. Just a warning about the difference between real behavior and the behavior that might be modeled.
  • @kuhl It looks like a bug in CCX. I asked AI which confirmed your conclusion - *MOHR COULOMB and *MOHR COULOMB HARDENING get assigned to the last material instead of the one they're under.
  • Well, knowing that that is good to know for a work around!
  • @Viktor, thank you for clarification.
Sign In or Register to comment.

Howdy, Stranger!

It looks like you're new here. If you want to get involved, click one of these buttons!